Abaqus Analysis User's Manual  


4.2.2 Abaqus/Explicit output variable identifiers

Product: Abaqus/Explicit  

References

Overview

Except for the information in the status file, results can be obtained from Abaqus/Explicit only by postprocessing.

The tables in this section list all of the output variables that are available in Abaqus/Explicit. These output variables can be requested for output to the results (.fil) file (see “Output to the data and results files,” Section 4.1.2) or as either field- or history-type output to the output database (.odb) file (see “Output to the output database,” Section 4.1.3). When the output variables are requested for output to the results file, Abaqus/Explicit will first output these variables to the selected results (.sel) file and will then convert the selected results file to the results file after the analysis completes.

Notation used in the output variable descriptions

The words .fil, .odb Field, and .odb History following the variable's description indicate the availability of the output variable. .fil refers to output to the results file. The output variable can be written to the respective file if the word "yes" appears after the category name; "no" means that the variable is not available to that file.

Direction definitions

The direction definitions depend on the variable type.

Direction definitions for element variables

For components of stress, strain, and similar material variables, 1, 2, and 3 refer to the directions in an orthogonal coordinate system. These are global directions for solid elements, surface directions for shell and membrane elements, and axial and transverse directions for beam and pipe elements. However, if a local orientation (“Orientations,” Section 2.2.5) is associated with the elements for which output is being requested, 1, 2, and 3 are local directions.

Direction definitions for nodal variables

For nodal variables, 1, 2, and 3 refer to the global directions (1=X, 2=Y, 3=Z except for axisymmetric elements, in which case 1=R, 2=Z). Even if a local coordinate system has been defined at a node (“Transformed coordinate systems,” Section 2.1.5), the data in the results file and the selected results file are still output in the global directions.

If nodal field output is requested for a node that has a local coordinate system defined, a quaternion representing the rotation from the global directions is written to the output database. Abaqus/CAE automatically uses this quaternion to transform the nodal results into the local directions. Nodal history data written to the output database are always stored in the global directions.

Direction definitions for integrated variables

For components of total force, total moment, and similar variables obtained through integration over a surface, the directions 1, 2, and 3 refer to directions in an orthogonal coordinate system. A fixed global coordinate system is used if the surface is specified directly for the integrated output request. If the surface is identified by an integrated output section definition (see “Integrated output section definition,” Section 2.5.1) that is associated with the integrated output request, a local coordinate system in the initial configuration can be specified and can translate or rotate with the deformation.

Distributed load output and user subroutines

Output can be requested for many of the distributed loads discussed in “Loads,” Section 33.4. However, contributions to these loads defined through user subroutines (see “Abaqus/Explicit subroutines,” Section 1.2 of the Abaqus User Subroutines Reference Manual) are not displayed.

Principal value output

Output of the principal values can be requested for stresses, logarithmic strains, and nominal strains. Either all principal values or the minimum, intermediate, or maximum values can be obtained. All principal values of tensor ABC are obtained with the request ABCP, and the minimum, intermediate, and maximum principal values are obtained with the requests ABCP1, ABCP2, and ABCP3, respectively. For three-dimensional, plane strain, and axisymmetric elements all three principal values are obtained. For plane stress, membrane, and shell elements only the in-plane principal values are obtained for history-type output, and the out-of-plane principal value cannot be requested. For field-type output, all three principal values are obtained through Abaqus/CAE. Principal values cannot be obtained for beam, pipe, and truss elements, and principal values of plastic strains cannot be requested.

If a principal value or an invariant is requested for field-type output, the output request is replaced with an output request for the components of the corresponding tensor. Abaqus/CAE calculates all principal values and invariants from these components. If a principal value is desired as history-type output, it must be requested explicitly since Abaqus/CAE does no calculations on history data.

Tensor output

Tensor variables that are written to the output database as field-type output are written as components in either the default directions defined by the convention given in “Orientations,” Section 2.2.5 (global directions for solid elements, surface directions for shell and membrane elements, and axial and transverse directions for beam and pipe elements), or the user-defined local system. Abaqus/CAE calculates all principal values and invariants from these components. See “Writing field output data,” Section 9.6.4 of the Abaqus Scripting User's Manual, for a description of the different types of tensor variables.

The components for tensor variables are written to the output database in single precision. Therefore, a small amount of precision roundoff error may occur when calculating the variables' principal values. Such roundoff error may be observed, for example, when analytically zero values are calculated as relatively small yet nonzero values.

Requesting output of components

Individual components of variables can be requested as history-type output in the output database for X–Y plotting in Abaqus/CAE. Individual component requests are not available for field-type output. If a particular component is desired for contouring in Abaqus/CAE, request field output of the generic variable (e.g., S for stress). Output for individual components of this field output can be requested within the Visualization module of Abaqus/CAE.

Element integration point variables

You can request element integration point variable output to the results or output database file (see “Element output” in “Output to the data and results files,” Section 4.1.2, and “Element output” in “Output to the output database,” Section 4.1.3).

Tensors and invariants


S
All stress components.
.fil: yes    .odb Field: yes    .odb History: yes   

MISESMAX
Maximum Mises stress among all of the section points. For a shell element it represents the maximum Mises value among all the section points in the layer, for a beam or pipe element it is the maximum Mises stress among all the section points in the cross-section, and for a solid element it represents the Mises stress at the integration points.
.fil: no    .odb Field: yes    .odb History: no   

Sij
-component of stress ().
.fil: no    .odb Field: no    .odb History: yes   

SP
All principal stress components.
.fil: yes    .odb Field: yes    .odb History: yes   

SPn
Minimum, intermediate, and maximum principal stress components (SP1 SP2 SP3).
.fil: no    .odb Field: no    .odb History: yes   

E
All infinitesimal strain components for geometrically linear analysis.
.fil: yes    .odb Field: yes    .odb History: yes   

Eij
-component of infinitesimal strain ().
.fil: no    .odb Field: no    .odb History: yes   

LE
All logarithmic strain components.
.fil: yes    .odb Field: yes    .odb History: yes   

LEij
-component of logarithmic strain ().
.fil: no    .odb Field: no    .odb History: yes   

LEP
All principal logarithmic strain components.
.fil: yes    .odb Field: yes    .odb History: yes   

LEPn
Minimum, intermediate, and maximum principal logarithmic strain components (LEP1 LEP2 LEP3).
.fil: no    .odb Field: no    .odb History: yes   

ER
All logarithmic strain rate components.
.fil: yes    .odb Field: yes    .odb History: yes   

ERij
-component of logarithmic strain rate().
.fil: no    .odb Field: no    .odb History: yes   

ERP
All principal logarithmic strain rate components.
.fil: yes    .odb Field: yes    .odb History: yes   

ERPn
Minimum, intermediate, and maximum principal strain rate components (ERP1 ERP2 ERP3).
.fil: no    .odb Field: no    .odb History: yes   

NE
All nominal strain components.
.fil: yes    .odb Field: yes    .odb History: yes   

NEij
-component of nominal strain ().
.fil: no    .odb Field: no    .odb History: yes   

NEP
All principal nominal strain components.
.fil: yes    .odb Field: yes    .odb History: yes   

NEPn
Minimum, intermediate, and maximum principal nominal strain components (NEP1 NEP2 NEP3).
.fil: no    .odb Field: no    .odb History: yes   

PE
All plastic strain components.
.fil: yes    .odb Field: yes    .odb History: yes   

PEij
-component of plastic strain ().
.fil: no    .odb Field: no    .odb History: yes   

PEP
All principal plastic strains.
.fil: no    .odb Field: yes    .odb History: yes   

PEPn
Minimum, intermediate, and maximum principal plastic strains.
.fil: no    .odb Field: no    .odb History: yes   

ERV
Volumetric strain rate.
.fil: yes    .odb Field: yes    .odb History: yes   

MISES
Mises equivalent stress, defined as , where is the deviatoric stress tensor, defined as , where is the stress and is the equivalent pressure stress.
.fil: yes    .odb Field: yes    .odb History: yes   

PRESS
Equivalent pressure stress, .
.fil: yes    .odb Field: yes    .odb History: yes   

TRIAX
Stress triaxiality, .
.fil: no    .odb Field: yes    .odb History: yes   

ALPHA
All total kinematic hardening shift tensor components.
.fil: yes    .odb Field: yes    .odb History: yes   

ALPHAij
-component of the total shift tensor ().
.fil: no    .odb Field: no    .odb History: yes   

ALPHAk
All kinematic hardening shift tensor components ().
.fil: no    .odb Field: yes    .odb History: yes   

ALPHAk_ij
-component of the kinematic hardening shift tensor ( and ).
.fil: no    .odb Field: no    .odb History: yes   

ALPHAN
All tensor components of all the kinematic hardening shift tensors, except the total shift tensor, ALPHA.
.fil: no    .odb Field: yes    .odb History: yes   

ALPHAP
All principal values of the total shift tensor.
.fil: yes    .odb Field: yes    .odb History: yes   

ALPHAPn
Minimum, intermediate, and maximum principal values of the total shift tensor (ALPHAP1 ALPHAP2 ALPHAP3).
.fil: no    .odb Field: no    .odb History: yes   

PEEQ
Equivalent plastic strain.

For porous metal plasticity PEEQ is the equivalent plastic strain in the matrix material defined as .

For cap plasticity PEEQ gives (the cap position).

For crushable foam plasticity with volumetric hardening PEEQ gives the volumetric compacting plastic strain defined as .

For crushable foam plasticity with isotropic hardening PEEQ gives the equivalent plastic strain defined as , where is the uniaxial compression yield stress.
.fil: yes    .odb Field: yes    .odb History: yes   

PEEQT
Equivalent plastic strain in uniaxial tension for cast iron, Mohr-Coulomb tension cutoff, and concrete damaged plasticity, which is defined as .
.fil: no    .odb Field: yes    .odb History: yes   

PEEQMAX
Maximum equivalent plastic strain, PEEQ, among all of the section points. For a shell element it represents the maximum PEEQ value among all the section points in the layer, for a beam or a pipe element it is the maximum PEEQ among all the section points in the cross-section, and for a solid element it represents the PEEQ at the integration points.
.fil: no    .odb Field: yes    .odb History: no   

DMICRTMAX
Maximum damage initiation among all of the section points and all of the damage initiation criteria.

This output variable generates three output quantities as follows:

DMICRTMAXVAL outputs the maximum damage initiation value.

DMICRTPOS outputs the section point in the layer in which the maximum damage initiation value occurred. For solid elements, the output value is one.

DMICRTTYPE outputs a value that represents the damage initiation criteria type that reached the maximum value in the element as follows:

For elements that have failure with progressive damage: 1-DUCTCRT, 2-SHRCRT, 3-JCCRT, 4-FLDCRT, 5-MSFLDCRT, 6-FLSDCRT, and 7-MKCRT.

For elements that have fiber-reinforced material damage: 11-HSNFTCRT, 12-HSNFCCRT, 13-HSNMTCRT, and 14-HSNMCCRT.

For cohesive elements with traction-separation behavior: 21-MAXSCRT, 22-MAXECRT, 23-QUADSCRT, and 24-QUADECRT.

The maximum damage initiation output values are retained across the requested output frames until a higher maximum damage initiation value is computed.
.fil: no    .odb Field: yes    .odb History: no   


Geometric quantities


COORD
Coordinates of the integration point for solid elements. These are the current coordinates if the large-displacement formulation is being used.
.fil: no    .odb Field: yes    .odb History: yes   

LOCALDIRn
Direction cosines of the local material directions for an anisotropic hyperelastic material model, or yarn direction cosines for a fabric material model. This variable is output automatically if any other element field output is requested for anisotropic hyperelastic or fabric material (see “Output” in “Anisotropic hyperelastic behavior,” Section 22.5.3, and “Output” in “Fabric material behavior,” Section 23.4.1).
.fil: no    .odb Field: automatic    .odb History: no   


Additional element stresses


TSHR
All transverse shear stress components for three-dimensional conventional shell elements.
.fil: yes    .odb Field: yes    .odb History: yes   

TSHR13
-component of transverse shear stress.
.fil: no    .odb Field: no    .odb History: yes   

TSHR23
-component of transverse shear stress.
.fil: no    .odb Field: no    .odb History: yes   


Energy densities


ENER
All energy densities.
.fil: yes    .odb Field: yes    .odb History: yes   

SENER
Elastic strain energy density, per unit volume.
.fil: no    .odb Field: no    .odb History: yes   

PENER
Energy dissipated by rate-independent and rate-dependent plasticity, per unit volume.
.fil: no    .odb Field: no    .odb History: yes   

CENER
Energy dissipated by viscoelasticity, per unit volume (not supported for hyperelastic and hyperfoam material models).
.fil: no    .odb Field: no    .odb History: yes   

VENER
Energy dissipated by viscous effects, per unit volume.
.fil: no    .odb Field: no    .odb History: yes   

DMENER
Energy dissipated by damage, per unit volume.
.fil: no    .odb Field: no    .odb History: yes   


State and field variables


SDV
Solution-dependent state variables.
.fil: yes    .odb Field: yes    .odb History: yes   

SDVn
Solution-dependent state variable n.
.fil: no    .odb Field: yes    .odb History: yes   

TEMP
Temperature.
.fil: yes    .odb Field: yes    .odb History: yes   

DENSITY
Material density.
.fil: no    .odb Field: yes    .odb History: yes   

FV
Field variables.
.fil: no    .odb Field: yes    .odb History: yes   

FVn
Field variable n.
.fil: no    .odb Field: no    .odb History: yes   


Composite failure measures


CFAILURE
All failure measure components.
.fil: no    .odb Field: yes    .odb History: no   

MSTRS
Maximum stress theory failure measure.
.fil: no    .odb Field: no    .odb History: no   

TSAIH
Tsai-Hill theory failure measure.
.fil: no    .odb Field: no    .odb History: no   

TSAIW
Tsai-Wu theory failure measure.
.fil: no    .odb Field: no    .odb History: no   

AZZIT
Azzi-Tsai-Hill theory failure measure.
.fil: no    .odb Field: no    .odb History: no   

MSTRN
Maximum strain theory failure measure.
.fil: no    .odb Field: no    .odb History: no   


Additional plasticity quantities


PEQC
All equivalent plastic strains, when the model has more than one yield/failure surface.
.fil: yes    .odb Field: yes    .odb History: yes   

PEQCn
nth equivalent plastic strain ().

For cap plasticity: PEQC provides equivalent plastic strains for all three possible yield/failure surfaces (Drucker-Prager failure surface - PEQC1, cap surface - PEQC2, and transition surface - PEQC3) and the total volumetric plastic strain (PEQC4). All identifiers also provide a yes/no flag (1/0 in the output database), telling whether the yield surface is currently active or not (AC YIELD: “actively yielding”).

When PEQC is requested as output to the output database, the active yield flags for each component are named AC YIELD1, AC YIELD2, etc.
.fil: no    .odb Field: no    .odb History: yes   


Porous metal plasticity quantities


VVF
Void volume fraction (porous metal plasticity).
.fil: yes    .odb Field: yes    .odb History: yes   

VVFG
Void volume fraction due to growth (porous metal plasticity).
.fil: yes    .odb Field: yes    .odb History: yes   

VVFN
Void volume fraction due to nucleation (porous metal plasticity).
.fil: yes    .odb Field: yes    .odb History: yes   


Concrete damaged plasticity


DAMAGEC
Compressive damage variable, .
.fil: no    .odb Field: yes    .odb History: yes   

DAMAGET
Tensile damage variable, .
.fil: no    .odb Field: yes    .odb History: yes   

SDEG
Scalar stiffness degradation variable, d.
.fil: no    .odb Field: yes    .odb History: yes   

PEEQ
Equivalent plastic strain in uniaxial compression, which is defined as .
.fil: no    .odb Field: yes    .odb History: yes   


Cracking model quantities


CKE
All cracking strain components.
.fil: yes    .odb Field: no    .odb History: no   

CKEij
-component of cracking strain.
.fil: no    .odb Field: no    .odb History: no   

CKLE
All cracking strain components in local crack axes.
.fil: yes    .odb Field: no    .odb History: no   

CKLEij
-component of cracking strain in local crack axes.
.fil: no    .odb Field: no    .odb History: no   

CKEMAG
Cracking strain magnitude, defined as .
.fil: yes    .odb Field: no    .odb History: no   

CKLS
All stress components in local crack axes.
.fil: yes    .odb Field: no    .odb History: no   

CKLSij
-component of stress in local crack axes.
.fil: no    .odb Field: no    .odb History: no   

CRACK
Crack orientations.
.fil: yes    .odb Field: no    .odb History: no   

CKSTAT
Crack status of each crack. CKSTAT can have the following values for each crack: 0.0=uncracked, 1.0=closed crack, 2.0=actively cracking, 3.0=crack closing/reopening.
.fil: yes    .odb Field: no    .odb History: no   


Failure with progressive damage


DMICRT
All active components of the damage initiation criteria.
.fil: no    .odb Field: yes    .odb History: yes   

DUCTCRT
Ductile damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

JCCRT
Johnson-Cook damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

SHRCRT
Shear damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

FLDCRT
Forming limit diagram (FLD) damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

FLSDCRT
Forming limit stress diagram (FLSD) damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

MSFLDCRT
Müschenborn-Sonne forming limit stress diagram (MSFLD) damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

MKCRT
Marciniak-Kuczynski (M-K) damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

SDEG
Overall scalar stiffness degradation.
.fil: no    .odb Field: yes    .odb History: yes   

ERPRATIO
Ratio of principal strain rates, , used for the MSFLD damage initiation criterion.
.fil: no    .odb Field: yes    .odb History: yes   

SHRRATIO
Shear stress ratio, , used for the shear damage initiation criterion.
.fil: no    .odb Field: yes    .odb History: yes   


Fiber-reinforced materials damage


DMICRT
All active components of the damage initiation criteria.
.fil: no    .odb Field: yes    .odb History: yes   

HSNFTCRT
Hashin's fiber tensile damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

HSNFCCRT
Hashin's fiber compressive damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

HSNMTCRT
Hashin's matrix tensile damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

HSNMCCRT
Hashin's matrix compressive damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

DAMAGEFT
Fiber tensile damage variable.
.fil: no    .odb Field: yes    .odb History: yes   

DAMAGEFC
Fiber compressive damage variable.
.fil: no    .odb Field: yes    .odb History: yes   

DAMAGEMT
Matrix tensile damage variable.
.fil: no    .odb Field: yes    .odb History: yes   

DAMAGEMC
Matrix compressive damage variable.
.fil: no    .odb Field: yes    .odb History: yes   

DAMAGESHR
Shear damage variable.
.fil: no    .odb Field: yes    .odb History: yes   


Fabric material


Output variable LOCALDIR (described above) is output automatically for fabric materials.

SFABRIC
All fabric stress components.
.fil: no    .odb Field: yes    .odb History: yes   

EFABRIC
All fabric strain components.
.fil: no    .odb Field: yes    .odb History: yes   

SFABRICij
-component of fabric stress ().
.fil: no    .odb Field: no    .odb History: yes   

EFABRICij
-component of fabric strain ().
.fil: no    .odb Field: no    .odb History: yes   


Equation of state


BURNF
Burn fraction of the ignition and growth material.
.fil: no    .odb Field: yes    .odb History: yes   

DBURNF
Reaction rate of the ignition and growth material.
.fil: no    .odb Field: yes    .odb History: yes   

RHOE
Density of the unreacted explosive in the ignition and growth material.
.fil: no    .odb Field: yes    .odb History: yes   

RHOP
Density of the reacted gas product in the ignition and growth material.
.fil: no    .odb Field: yes    .odb History: yes   

PALPH
Distension, , of the porous material.
.fil: no    .odb Field: yes    .odb History: yes   

PALPHMIN
Minimum value, , of the distension attained during plastic compaction of the porous material.
.fil: no    .odb Field: yes    .odb History: yes   


Rebar quantities


RBFOR
Force in rebar.
.fil: yes    .odb Field: yes    .odb History: yes   

RBANG
Angle, in degrees, between rebar and the user-specified isoparametric direction. Available only for shell and membrane elements.
.fil: yes    .odb Field: yes    .odb History: yes   

RBROT
Change in angle, in degrees, between rebar and the user-specified isoparametric direction. Available only for shell and membrane elements.
.fil: yes    .odb Field: yes    .odb History: yes   


Integration point coordinates


COORD
Coordinates of element integration point.
.fil: no    .odb Field: yes    .odb History: yes   


Coupled thermal-stress elements


HFL
Current magnitude and components of the heat flux per unit area vector.
.fil: yes    .odb Field: yes    .odb History: yes   

HFLM
Current magnitude of the heat flux per unit area vector.
.fil: no    .odb Field: no    .odb History: yes   

HFLn
Component n of the heat flux vector ().
.fil: no    .odb Field: no    .odb History: yes   


Cohesive elements


MAXSCRT
Maximum nominal stress damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

MAXECRT
Maximum nominal strain damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

QUADSCRT
Quadratic nominal stress damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

QUADECRT
Quadratic nominal strain damage initiation criterion.
.fil: no    .odb Field: no    .odb History: yes   

DMICRT
All active components of the damage initiation criteria.
.fil: no    .odb Field: yes    .odb History: yes   

SDEG
Overall scalar stiffness degradation.
.fil: no    .odb Field: yes    .odb History: yes   

STATUS
Status of the element (the status of an element is 1.0 if the element is active, 0.0 if the element is not).
.fil: no    .odb Field: yes    .odb History: yes   


Eulerian elements


EVF
Eulerian volume fraction. Output includes volume fraction data for each material defined in the Eulerian section, plus the volume fraction of void.
.fil: no    .odb Field: yes    .odb History: yes   

DENSITYVAVG
Density, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

MISESVAVG
Mises stress, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

PEVAVG
Plastic strain components, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

PEEQVAVG
Equivalent plastic strain, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

PRESSVAVG
Equivalent pressure stress, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

SVAVG
Stress components, computed as a volume fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   

TEMPMAVG
Temperature, computed as a mass fraction weighted average of all materials in the element.
.fil: no    .odb Field: yes    .odb History: no   


Element section variables

You can request element section variable output to the results or output database file (see “Element output” in “Output to the data and results files,” Section 4.1.2, and “Element output” in “Output to the output database,” Section 4.1.3). These variables are available only for beam, pipe, and shell elements with the exception of STH, which is also available for membrane elements. They are defined for particular elements in the element descriptions in Part VI, “Elements.”

STH
Section thickness (shell and membrane elements only).
.fil: yes    .odb Field: yes    .odb History: yes   

SF
All section resultant components, both translational (forces) and rotational (moments).
.fil: yes    .odb Field: yes    .odb History: yes   

SFn
Section force component n, for conventional shells; for continuum shells; for beams and pipes.
.fil: no    .odb Field: no    .odb History: yes   

SMn
Section moment component n, .
.fil: no    .odb Field: no    .odb History: yes   

SE
All section nominal strains, both translational and rotational (e.g., midplane strain and curvature in shells).
.fil: yes    .odb Field: yes    .odb History: yes   

SEn
Section nominal strain component n, for shells; for beams and pipes.
.fil: no    .odb Field: no    .odb History: yes   

SKn
Section curvature change or twist n, .
.fil: no    .odb Field: no    .odb History: yes   

SSAVG
All average membrane and transverse shear stress components (shell elements only).
.fil: yes    .odb Field: yes    .odb History: no   

SSAVGn
Average membrane or transverse shear stress component n, (shell elements only).
.fil: no    .odb Field: no    .odb History: yes   


Whole element variables

You can request whole element variable output to the results or output database file (see “Element output” in “Output to the data and results files,” Section 4.1.2, and “Element output” in “Output to the output database,” Section 4.1.3).

ELEN
All energy magnitudes in the element.
.fil: yes    .odb Field: yes    .odb History: yes   

ELSE
Total elastic strain energy in the element (includes energy in transverse shear deformation in shells).
.fil: no    .odb Field: yes    .odb History: yes   

ELCD
Total energy dissipated in the element by viscoelastic deformation. (Not supported for hyperelastic and hyperfoam material models.)
.fil: no    .odb Field: yes    .odb History: yes   

ELPD
Total energy dissipated in the element by rate-independent and rate-dependent plastic deformation.
.fil: no    .odb Field: yes    .odb History: yes   

ELVD
Total energy dissipated in the element by viscous effects. This includes bulk viscosity and material damping.
.fil: no    .odb Field: yes    .odb History: yes   

ELASE
Total “artificial” strain energy in the element. This includes hourglass energy and drilling stiffness energy in shells.
.fil: no    .odb Field: yes    .odb History: yes   

ELIHE
Internal heat energy in the element.
.fil: no    .odb Field: yes    .odb History: yes   

ELDMD
Total energy dissipated in the element by damage.
.fil: no    .odb Field: yes    .odb History: yes   

ELDC
Total energy dissipated in the element by distortion control.
.fil: no    .odb Field: yes    .odb History: yes   

ELEDEN
All element energy density components.
.fil: no    .odb Field: yes    .odb History: no   

ESEDEN
Total elastic strain energy density in the element.
.fil: no    .odb Field: yes    .odb History: no   

EPDDEN
Total energy dissipated per unit volume in the element by rate-independent and rate-dependent plastic deformation.
.fil: no    .odb Field: yes    .odb History: no   

ECDDEN
Total energy dissipated per unit volume in the element by viscoelasticity.
.fil: no    .odb Field: yes    .odb History: no   

EVDDEN
Total energy dissipated per unit volume in the element by viscous effects.
.fil: no    .odb Field: yes    .odb History: no   

EASEDEN
Total “artificial” strain energy density in the element (energy associated with constraints used to remove singular modes, such as hourglass control).
.fil: no    .odb Field: yes    .odb History: no   

EIHEDEN
Internal heat energy density in the element.
.fil: no    .odb Field: yes    .odb History: no   

EDMDDEN
Total energy dissipated per unit volume in the element by damage.
.fil: no    .odb Field: yes    .odb History: no   

EDCDEN
Total energy dissipated per unit volume in the element by distortion control.
.fil: no    .odb Field: yes    .odb History: no   

EDT
Element stable time increment.
.fil: yes    .odb Field: yes    .odb History: yes   

EMSF
Element mass scaling factor.
.fil: yes    .odb Field: yes    .odb History: yes   

STATUS
Status of element (material failure with progressive damage, shear failure model, tensile failure model, porous failure criterion, brittle failure model, Johnson-Cook plasticity model, and VUMAT). The status of an element is 1.0 if the element is active, 0.0 if the element is not.
.fil: yes    .odb Field: yes    .odb History: yes   

EVOL
Current element volume. (Only available for continuum and structural elements not using general beam or shell section definitions.)
.fil: no    .odb Field: yes    .odb History: no   

NFORC
Forces at the nodes of an element from both the hourglass and the regular deformation modes of that element (internal forces in the global coordinate system).
.fil: no    .odb Field: yes    .odb History: yes   

GRAV
Uniformly distributed gravity load.
.fil: no    .odb Field: yes    .odb History: no   

SBF
Stagnation body force.
.fil: no    .odb Field: yes    .odb History: no   

BF
Uniformly distributed body force, including viscous body force.
.fil: no    .odb Field: yes    .odb History: no   

EDMICRTMAX
Whole shell element maximum damage initiation output among all of the layers, all of the damage initiation criteria, and for fully integrated elements across all of the integration points.

This output variable is the same as DMICRTMAX output for solid and beam elements but complements the DMICRTMAX output variable for composite shell elements because it extracts the maximum damage initiation across all of the layers.

This output variable generates four element output quantities as follows:

EDMICRTMAXVAL outputs the maximum damage initiation value in the entire element.

EDMICRTLAYER outputs the layer number in which the maximum damage initiation value occurred.

EDMICRTTYPE outputs a value that represents the damage initiation criteria type that reached the maximum value in the element, as described in the DMICRTMAX output variable description.

EDMICRTINTP outputs the integration point number for which the maximum damage value occurred. For reduced-integration elements, the output value is one.

The maximum damage initiation output values are retained across the requested output frames until a higher maximum damage initiation value is computed.
.fil: no    .odb Field: yes    .odb History: no   


Connector elements


CTF
All components of connector total forces and moments.
.fil: yes    .odb Field: yes    .odb History: yes   

CTFn
Connector total force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CTMn
Connector total moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CEF
All components of connector elastic forces and moments.
.fil: yes    .odb Field: yes    .odb History: yes   

CEFn
Connector elastic force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CEMn
Connector elastic moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CUE
Elastic displacements and rotations in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CUEn
Elastic displacement in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CUREn
Elastic rotation in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CUP
Plastic relative displacements and rotations in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CUPn
Plastic relative displacement in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CURPn
Plastic relative rotation in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CUPEQ
Equivalent plastic relative displacements and rotations in all directions, and equivalent plastic relative motion for a coupled plasticity definition.
.fil: yes    .odb Field: yes    .odb History: yes   

CUPEQn
Equivalent plastic relative displacement in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CURPEQn
Equivalent plastic relative rotation in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CUPEQC
Equivalent plastic relative motion for a coupled plasticity definition.
.fil: no    .odb Field: no    .odb History: yes   

CALPHAF
All components of connector kinematic hardening shift forces and moments.
.fil: yes    .odb Field: no    .odb History: yes   

CALPHAFn
Connector kinematic hardening shift force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CALPHAMn
Connector kinematic hardening shift moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CVF
All components of connector viscous forces and moments.
.fil: yes    .odb Field: yes    .odb History: yes   

CVFn
Connector viscous force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CVMn
Connector viscous moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CUF
All components of connector uniaxial forces and moments.
.fil: no    .odb Field: yes    .odb History: yes   

CUFn
Connector uniaxial force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CUMn
Connector uniaxial moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CSF
All components of connector friction forces and moments.
.fil: yes    .odb Field: no    .odb History: yes   

CSFn
Connector friction force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CSMn
Connector friction moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CSFC
Connector friction force in the instantaneous slip direction. Available only if friction is defined in the slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CNF
All components of connector friction-generating contact forces and moments.
.fil: yes    .odb Field: no    .odb History: yes   

CNFn
Connector friction-generating contact force component n (n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CNMn
Connector friction-generating contact moment component n (n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CNFC
Connector friction-generating contact force in the instantaneous slip direction. Available only if friction is defined in the slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CDMG
All components of the overall damage variable.
.fil: yes    .odb Field: yes    .odb History: yes   

CDMGn
Overall damage variable component n ().
.fil: no    .odb Field: no    .odb History: yes   

CDMGRn
Overall damage variable component n ().
.fil: no    .odb Field: no    .odb History: yes   

CDIF
Components of connector force-based damage initiation criterion in all directions.
.fil: yes    .odb Field: no    .odb History: yes   

CDIFn
Connector force-based damage initiation criterion in the n-translation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIFRn
Connector force-based damage initiation criterion in the n-rotation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIFC
Connector force-based damage initiation criterion in the instantaneous slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CDIM
Components of connector motion-based damage initiation criterion in all directions.
.fil: yes    .odb Field: no    .odb History: yes   

CDIMn
Connector motion-based damage initiation criterion in the n-translation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIMRn
Connector motion-based damage initiation criterion in the n-rotation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIMC
Connector motion-based damage initiation criterion in the instantaneous slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CDIP
Components of connector plastic motion-based damage initiation criterion in all directions (including the instantaneous slip direction).
.fil: yes    .odb Field: yes    .odb History: yes   

CDIPn
Connector plastic motion-based damage initiation criterion in the n-translation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIPRn
Connector plastic motion-based damage initiation criterion in the n-rotation direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDIPC
Connector plastic motion-based damage initiation criterion in the instantaneous slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CSLST
All flags for connector stop and connector lock status.
.fil: yes    .odb Field: no    .odb History: yes   

CSLSTi
Flag for connector stop and connector lock status in the i-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CASU
Components of accumulated slip in all directions.
.fil: yes    .odb Field: no    .odb History: yes   

CASUn
Connector accumulated slip in the n-direction (n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CASURn
Connector angular accumulated slip in the n-direction (n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CASUC
Connector accumulated slip in the instantaneous slip direction. Available only if friction is defined in the slip direction.
.fil: no    .odb Field: no    .odb History: yes   

CIVC
Connector instantaneous velocity in the slip direction. Available only if friction is defined in the slip direction.
.fil: yes    .odb Field: no    .odb History: yes   

CRF
All components of connector reaction forces and moments.
.fil: yes    .odb Field: no    .odb History: yes   

CRFn
Connector reaction force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CRMn
Connector reaction moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CCF
All components of connector concentrated forces and moments.
.fil: yes    .odb Field: no    .odb History: yes   

CCFn
Connector concentrated force component n ().
.fil: no    .odb Field: no    .odb History: yes   

CCMn
Connector concentrated moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

CP
Relative positions in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CPn
Relative position in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CPRn
Relative angular position in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CU
Relative displacements and rotations in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CUn
Relative displacement in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CURn
Relative rotation in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CCU
Constitutive displacements and rotations in all directions.
.fil: yes    .odb Field: no    .odb History: yes   

CCUn
Constitutive displacement in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CCURn
Constitutive rotation in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CV
Relative velocities in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CVn
Relative velocity in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CVRn
Relative angular velocity in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CA
Relative accelerations in all directions.
.fil: yes    .odb Field: yes    .odb History: yes   

CAn
Relative acceleration in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CARn
Relative angular acceleration in the n-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CFAILST
All flags for connector failure status.
.fil: yes    .odb Field: yes    .odb History: yes   

CFAILSTi
Flag for connector failure status in the i-direction ().
.fil: no    .odb Field: no    .odb History: yes   

CDERU
Connector derived displacement.
.fil: no    .odb Field: yes    .odb History: yes   

CDERF
Connector derived force.
.fil: no    .odb Field: yes    .odb History: yes   


Element face variables

You can request element face variable output to the output database file (see “Element output” in “Output to the output database,” Section 4.1.3). These variables are available only for shell, membrane, and solid elements.

P
Uniformly distributed pressure load on element faces. When the pressure is defined using *DLOAD, the variable name is changed automatically to PDLOAD.
.fil: no    .odb Field: yes    .odb History: no   

STAGP
Stagnation pressure load on element faces.
.fil: no    .odb Field: yes    .odb History: no   

VP
Viscous pressure load on element faces.
.fil: no    .odb Field: yes    .odb History: no   

IWCONWEP
Air blast pressure load from the CONWEP model on element faces.
.fil: no    .odb Field: yes    .odb History: no   

TRNOR
Normal component (component along face normal) of traction load on element faces.
.fil: no    .odb Field: yes    .odb History: no   

TRSHR
Shear component (component along face tangent) of traction load on element faces.
.fil: no    .odb Field: yes    .odb History: no   


Nodal variables

You can request nodal variable output to the results or output database file (see “Node output” in “Output to the data and results files,” Section 4.1.2, and “Node output” in “Output to the output database,” Section 4.1.3).

COORD
Coordinates of the node. These are the current coordinates if the large-displacement formulation is being used.
.fil: yes    .odb Field: yes    .odb History: yes   

COORn
Coordinate n ().
.fil: no    .odb Field: no    .odb History: yes   

U
Displacement components.

Results file and field-type output: both translation and rotation.

History-type output: translation only. Rotation results should be requested by components.
.fil: yes    .odb Field: yes    .odb History: yes   

UT
Translational displacement components.
.fil: no    .odb Field: yes    .odb History: yes   

UR
Rotational displacement components.
.fil: no    .odb Field: yes    .odb History: yes   

Un
displacement component ().
.fil: no    .odb Field: no    .odb History: yes   

URn
rotation component ().
.fil: no    .odb Field: no    .odb History: yes   

V
Velocity components (both translation and rotation).

Results file and field-type output: both translation and rotation.

History-type output: translation only. Rotation results should be requested by components.
.fil: yes    .odb Field: yes    .odb History: yes   

VT
Translational velocity components.
.fil: no    .odb Field: yes    .odb History: yes   

VR
Rotational velocity components.
.fil: no    .odb Field: yes    .odb History: yes   

Vn
velocity component ().
.fil: no    .odb Field: no    .odb History: yes   

VRn
rotational velocity component ().
.fil: no    .odb Field: no    .odb History: yes   

A
Acceleration components (both translation and rotation).

Results file and field-type output: both translation and rotation.

History-type output: translation only. Rotation results should be requested by components.
.fil: yes    .odb Field: yes    .odb History: yes   

AT
Translational acceleration components.
.fil: no    .odb Field: yes    .odb History: yes   

AR
Rotational acceleration components.
.fil: no    .odb Field: yes    .odb History: yes   

An
acceleration component ().
.fil: no    .odb Field: no    .odb History: yes   

ARn
rotational acceleration component ().
.fil: no    .odb Field: no    .odb History: yes   

POR
Acoustic pressure at a node.
.fil: yes    .odb Field: yes    .odb History: yes   

PABS
Acoustic absolute pressure at a node.
.fil: yes    .odb Field: yes    .odb History: yes   

NT
All temperature values at a node. Available only for coupled thermal-stress analysis.
.fil: yes    .odb Field: yes    .odb History: yes   

NTn
Temperature degree of freedom n at a node (). Available only for coupled thermal-stress analysis.
.fil: no    .odb Field: no    .odb History: yes   

RF
Reaction force and moment components.

Results file and field-type output: both translation and rotation.

History-type output: translation only. Rotation results should be requested by components.
.fil: yes    .odb Field: yes    .odb History: yes   

RT
Reaction force components.
.fil: no    .odb Field: yes    .odb History: yes   

RM
Reaction moment components.
.fil: no    .odb Field: yes    .odb History: yes   

RFn
Reaction force component n () (conjugate to prescribed displacement ).
.fil: no    .odb Field: no    .odb History: yes   

RFL
All reaction flux values. Available only for coupled thermal-stress analysis.
.fil: yes    .odb Field: yes    .odb History: yes   

RFLn
Reaction flux value n at a node (). Available only for coupled thermal-stress analysis.
.fil: no    .odb Field: yes    .odb History: yes   

RMn
Reaction moment component n () (conjugate to prescribed rotation ).
.fil: no    .odb Field: no    .odb History: yes   

CF
All components of point loads and concentrated moments.
.fil: no    .odb Field: yes    .odb History: yes   

CFn
Point load component n ().
.fil: no    .odb Field: no    .odb History: yes   

CMn
Point moment component n ().
.fil: no    .odb Field: no    .odb History: yes   

NVF
Nodal volume fraction.
.fil: no    .odb Field: yes    .odb History: no   

TIEDSTATUS
Status of the tied slave nodes (the status of a slave node is 2 if the slave node is not tied, 1 if the slave node is tied, and 0 for nodes that do not participate in a tie constraint).
.fil: no    .odb Field: yes    .odb History: no   

TIEADJUST
Position adjustment vector components of the tied slave nodes.
.fil: no    .odb Field: yes    .odb History: no   


Fluid cavity variables


PCAV
Fluid cavity gauge pressure.
.fil: yes    .odb Field: no    .odb History: yes   

CVOL
Fluid cavity volume.
.fil: yes    .odb Field: no    .odb History: yes   

CTEMP
Fluid cavity temperature for an ideal gas model used under adiabatic conditions.
.fil: no    .odb Field: no    .odb History: yes   

CSAREA
Fluid cavity surface area.
.fil: no    .odb Field: no    .odb History: yes   

CLAREA
Fluid cavity unblocked leakage area.
.fil: no    .odb Field: no    .odb History: yes   

CBLARAT
Ratio of the blocked leakage area to the unblocked leakage area.
.fil: no    .odb Field: no    .odb History: yes   

CMASS
Mass of the fluid contained in a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

APCAV
Average gauge pressures for multiple fluid cavities.
.fil: no    .odb Field: no    .odb History: yes   

TCVOL
Total volume of multiple fluid cavities.
.fil: no    .odb Field: no    .odb History: yes   

ACTEMP
Average fluid cavity temperature for an ideal gas model used under adiabatic conditions for multiple fluid cavities.
.fil: no    .odb Field: no    .odb History: yes   

TCSAREA
Total surface area of multiple fluid cavities.
.fil: no    .odb Field: no    .odb History: yes   

TCMASS
Total mass of the fluid contained in the multiple fluid cavities.
.fil: no    .odb Field: no    .odb History: yes   

CMF
Molecular mass fraction of fluid species contained in a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

CMFL
Mass flow rate out of a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

CMFLT
Accumulated mass flow out of a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

CEFL
Heat energy flow rate out of a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

CEFLT
Accumulated heat energy flow out of a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

MINFL
Inflator mass flow rate into a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

MINFLT
Accumulated inflator mass flow into a fluid cavity.
.fil: no    .odb Field: no    .odb History: yes   

TINFL
Inflator temperature.
.fil: no    .odb Field: no    .odb History: yes   


Surface variables

You can request surface variable output to the output database file (see “Surface output in Abaqus/Standard and Abaqus/Explicit” in “Output to the output database,” Section 4.1.3); additional information on these variables is provided in “Defining general contact interactions in Abaqus/Explicit,” Section 35.4.1; “Defining contact pairs in Abaqus/Explicit,” Section 35.5.1; and “Thermal contact properties,” Section 36.2.1.

Mechanical analysis–nodal quantities


CFORCE
Contact normal force (CNORMF) and frictional shear force (CSHEARF).
.fil: no    .odb Field: yes    .odb History: no   

CSTRESS
Contact pressure (CPRESS) and frictional shear stress (CSHEAR). CSHEAR is not available for general contact analyses.
.fil: no    .odb Field: yes    .odb History: no   

CTHICK
Contact thickness in general contact or contact pairs.
.fil: no    .odb Field: yes    .odb History: no   

CSMAXSCRT
Maximum stress-based damage initiation criterion for cohesive surfaces in general contact.
.fil: no    .odb Field: yes    .odb History: no   

CSQUADSCRT
Quadratic stress-based damage initiation criterion for cohesive surfaces in general contact.
.fil: no    .odb Field: yes    .odb History: no   

CSMAXUCRT
Maximum separation-based damage initiation criterion for cohesive surfaces in general contact.
.fil: no    .odb Field: yes    .odb History: no   

CSQUADUCRT
Quadratic separation-based damage initiation criterion for cohesive surfaces in general contact.
.fil: no    .odb Field: yes    .odb History: no   

CSDMG
Damage variable for cohesive surfaces in general contact.
.fil: no    .odb Field: yes    .odb History: no   

FSLIP
Length of contact slip path at slave nodes during contact (FSLIPEQ) and in some cases (see “Defining contact pairs in Abaqus/Explicit,” Section 35.5.1) components of net contact slip in local tangent directions (FSLIP1 and FSLIP2). These variables remain constant while a slave node is not in contact.
.fil: no    .odb Field: yes    .odb History: no   

FSLIPR
Magnitude of contact slip rate at slave nodes during contact (FSLIPR) and in some cases (see “Defining contact pairs in Abaqus/Explicit,” Section 35.5.1) components of contact slip rate in local tangent directions (FSLIPR1 and FSLIPR2). These variables are set to zero while a slave node is not in contact.
.fil: no    .odb Field: yes    .odb History: no   

BONDSTAT
Spot weld bond status.
.fil: no    .odb Field: no    .odb History: yes   

BONDLOAD
Spot weld bond load.
.fil: no    .odb Field: no    .odb History: yes   


Crack bond failure quantities


DBT
Time when bond failure occurs.
.fil: no    .odb Field: yes    .odb History: no   

DBS
All components of remaining stress in the failed bond.
.fil: no    .odb Field: yes    .odb History: no   

DBSF
Fraction of stress that remains at bond failure.
.fil: no    .odb Field: yes    .odb History: no   

BDSTAT
Bond state (the state is 1.0 if bonded, 0.0 if unbonded).
.fil: no    .odb Field: yes    .odb History: no   

OPENBC
Relative displacement behind crack when fracture criterion is met.
.fil: no    .odb Field: yes    .odb History: no   

CRSTS
All components of critical stress at failure.
.fil: no    .odb Field: yes    .odb History: no   

ENRRT
All components of strain energy release rate.
.fil: no    .odb Field: yes    .odb History: no   

EFENRRTR
Effective energy release rate ratio.
.fil: no    .odb Field: yes    .odb History: no   


Mechanical analysis–whole surface quantities


CFN
Total force due to contact pressure (CFNn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CFNM
Magnitude of total force due to contact pressure.
.fil: no    .odb Field: no    .odb History: yes   

CFS
Total force due to frictional stress (CFSn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CFSM
Magnitude of total force due to frictional stress.
.fil: no    .odb Field: no    .odb History: yes   

CFT
Total force due to contact pressure and frictional stress (CFTn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CFTM
Magnitude of total force due to contact pressure and frictional stress.
.fil: no    .odb Field: no    .odb History: yes   

CMN
Total moment about the origin due to contact pressure (CMNn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CMNM
Magnitude of total moment about the origin due to contact pressure.
.fil: no    .odb Field: no    .odb History: yes   

CMS
Total moment about the origin due to frictional stress (CMSn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CMSM
Magnitude of total moment about the origin due to frictional stress.
.fil: no    .odb Field: no    .odb History: yes   

CMT
Total moment about the origin due to contact pressure and frictional stress (CMTn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

CMTM
Magnitude of total moment about the origin due to contact pressure and frictional stress.
.fil: no    .odb Field: no    .odb History: yes   

CAREA
Total area in contact.
.fil: no    .odb Field: no    .odb History: yes   

XN
Center of the total force due to contact pressure (XNn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

XS
Center of the total force due to frictional stress (XSn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   

XT
Center of the total force due to contact pressure and frictional stress (XTn, n = 1, 2, 3).
.fil: no    .odb Field: no    .odb History: yes   


Fully coupled temperature-displacement analysis


HFL
Heat flux per unit area leaving the surface.
.fil: no    .odb Field: yes    .odb History: no   

HFLA
HFL multiplied by the nodal area.
.fil: no    .odb Field: yes    .odb History: no   

HTL
Time integrated HFL.
.fil: no    .odb Field: yes    .odb History: no   

HTLA
HTL multiplied by the nodal area.
.fil: no    .odb Field: yes    .odb History: no   

SFDR
Heat flux per unit area due to frictional dissipation.
.fil: no    .odb Field: yes    .odb History: no   

SFDRA
SFDR multiplied by the nodal area.
.fil: no    .odb Field: yes    .odb History: no   

SFDRT
Time integrated SFDR.
.fil: no    .odb Field: yes    .odb History: no   

SFDRTA
SFDRT multiplied by the nodal area.
.fil: no    .odb Field: yes    .odb History: no   


Integrated variables

You can request integrated variable output to the output database (see “Integrated output in Abaqus/Explicit” in “Output to the output database,” Section 4.1.3). The output quantity is computed by integration over a surface or an element set that is specified either directly in the integrated output request or by associating an integrated output section definition (see “Integrated output section definition,” Section 2.5.1) or an element set definition with the integrated output request.

The components of the vector output variables are given with respect to a global coordinate system when no integrated output section definition is associated with the integrated output request. When an integrated output section is associated with the integrated output request and a local coordinate system is defined for the integrated output section, the components are given in the local system. The local system will rotate with the deformation if a reference node with rotation degrees of freedom is associated with the section definition.


SOAREA
Area of the surface as projected onto a plane normal to the average surface normal.
.fil: no    .odb Field: no    .odb History: yes   

SOF
Total force transmitted through the surface.
.fil: no    .odb Field: no    .odb History: yes   

SOM
Total moment transmitted through the surface. The moment of the forces transmitted through the surface is taken about the current location of the reference node if one is specified on an integrated output section and is associated with the integrated output request. The moment is taken about the global origin either if no section definition is associated with the integrated output request or if there is no reference node defined in the associated section definition.
.fil: no    .odb Field: no    .odb History: yes   

MASS
Total mass of the element set.
.fil: no    .odb Field: no    .odb History: yes   

DMASS
Total mass change in percentage of the element set due to mass scaling.
.fil: no    .odb Field: no    .odb History: yes   

UCOM
Equivalent rigid-body translational displacement of the element set.
.fil: no    .odb Field: no    .odb History: yes   

VCOM
Equivalent rigid-body translational velocity of the element set.
.fil: no    .odb Field: no    .odb History: yes   

ACOM
Equivalent rigid-body translational acceleration of the element set.
.fil: no    .odb Field: no    .odb History: yes   

COORDCOM
Coordinates of the center of mass of the element set.
.fil: no    .odb Field: no    .odb History: yes   

MASSEUL
Total mass of each Eulerian material instance in the element set.
.fil: no    .odb Field: no    .odb History: yes   

VOLEUL
Total volume of each Eulerian material instance in the element set.
.fil: no    .odb Field: no    .odb History: yes   


Total energy output

You can request total energy variable output to the results or output database file (see “Total energy output” in “Output to the data and results files,” Section 4.1.2, and “Total energy output” in “Output to the output database,” Section 4.1.3). All of these variables are written when total energy output is requested. Energy history totals can be requested to the output database for part of the model as well as the whole model.

ALLAE
“Artificial” strain energy associated with constraints used to remove singular modes (such as hourglass control) and with constraints used to make the drill rotation follow the in-plane rotation of the shell elements.
.fil: yes    .odb Field: no    .odb History: yes   

ALLCD
Energy dissipated by viscoelasticity. (Not supported for hyperelastic and hyperfoam material models).
.fil: yes    .odb Field: no    .odb History: yes   

ALLFD
Total energy dissipated through frictional effects. (Available only for the whole model).
.fil: yes    .odb Field: no    .odb History: yes   

ALLIE
Total strain energy. (ALLIE=ALLSE + ALLPD + ALLCD + ALLAE + ALLDMD+ ALLDC+ ALLFC.)
.fil: yes    .odb Field: no    .odb History: yes   

ALLKE
Kinetic energy.
.fil: yes    .odb Field: no    .odb History: yes   

ALLPD
Energy dissipated by rate-independent and rate-dependent plastic deformation.
.fil: yes    .odb Field: no    .odb History: yes   

ALLSE
Recoverable strain energy.
.fil: yes    .odb Field: no    .odb History: yes   

ALLVD
Energy dissipated by viscous effects.
.fil: yes    .odb Field: no    .odb History: yes   

ALLWK
External work. (Available only for the whole model).
.fil: yes    .odb Field: no    .odb History: yes   

ALLIHE
Internal heat energy.
.fil: yes    .odb Field: no    .odb History: yes   

ALLHF
External heat energy through external fluxes.
.fil: yes    .odb Field: no    .odb History: yes   

ALLDMD
Energy dissipated by damage.
.fil: yes    .odb Field: no    .odb History: yes   

ALLDC
Energy dissipated by distortion control.
.fil: yes    .odb Field: no    .odb History: yes   

ALLFC
Fluid cavity energy, defined as the negative of the work done by all fluid cavities. (Available only for the whole model.)
.fil: no    .odb Field: no    .odb History: yes   

ALLPW
Work done by contact penalties, including general contact and penalty/kinematic contact pairs. (Available only for the whole model.)
.fil: no    .odb Field: no    .odb History: yes   

ALLCW
Work done by constraint penalties. (Available only for the whole model.)
.fil: no    .odb Field: no    .odb History: yes   

ALLMW
Work done in propelling mass added in mass scaling. (Available only for the whole model.)
.fil: no    .odb Field: no    .odb History: yes   

ETOTAL
Energy balance defined as: ALLKE + ALLIE + ALLVD + ALLFD + ALLIHE – ALLWK – ALLPW – ALLCW – ALLMW – ALLHF. (Available only for the whole model.)
.fil: yes    .odb Field: no    .odb History: yes   


Time increment and mass output

The DT and DMASS variables are always written when any results file output is requested (see “Output to the Abaqus/Explicit results file” in “Output to the data and results files,” Section 4.1.2). You can request output of the time increment and the steady-state detection variables SSPEEQ, SSSPRD, SSFORC, and SSTORQ to the output database (see “Time incrementation output in Abaqus/Explicit” in “Output to the output database,” Section 4.1.3).

DT
Time increment.
.fil: yes    .odb Field: no    .odb History: yes   

DMASS
Percent change in mass of the model due to mass scaling.
.fil: yes    .odb Field: no    .odb History: yes   

SSPEEQ
Steady-state equivalent plastic strain norms.
.fil: no    .odb Field: no    .odb History: yes   

SSPEEQn
Steady-state equivalent plastic strain norm n.
.fil: no    .odb Field: no    .odb History: yes   

SSSPRD
Steady-state spread strain norms.
.fil: no    .odb Field: no    .odb History: yes   

SSSPRDn
Steady-state spread norm n.
.fil: no    .odb Field: no    .odb History: yes   

SSFORC
Steady-state force norms.
.fil: no    .odb Field: no    .odb History: yes   

SSFORCn
Steady-state force norm n.
.fil: no    .odb Field: no    .odb History: yes   

SSTORQ
Steady-state torque norms.
.fil: no    .odb Field: no    .odb History: yes   

SSTORQn
Steady-state torque norm n.
.fil: no    .odb Field: no    .odb History: yes